Back to tabs
Default directory
Placing symbols
Editing symbols
  

Using welding symbols in drawings

Setting the default directory for welding symbols


When you place a welding symbol in a drawing, you are creating an instance of a generic symbol. The symbol file is located in the symbol library on the hard drive of your workstation. To simplify the symbol placement process, set the directory path to the symbol library as follows:

  1. From the tool bar at the top of the Pro/Engineer screen, choose Utilities > Preferences > Edit Config.
  2. Type config.pro (the local configuration file) in the text box at the bottom of the screen.
  3. Press enter to begin editing the file in Pro/Table.
  4. When the Pro/Table window appears, press F4 to display a list of configuration file options.
  5. Select pro_symbol_dir.
  6. Enter the directory for the welding symbol library in the right hand column. The current directory is, c:\ptc\proe2000i\symbols\library_syms\weldsymlib \ansi_weld\simple.
  7. Chose File > Exit at the top left of the window. This will exit and automatically save the changes you made to the config.pro file.
  8. Exit and restart Pro/Engineer or choose Utilities > Preferences > Load Config from the tool bar.

Placing welding symbols in a drawing

  1. From the Menu Manager choose DETAIL > Create > Symbol > Instance.
  2. The Symbol Instance dialog box will open.
  3. Click the Retrieve… button to retrieve a symbol from the symbols library or click the Pick Inst… button to select a symbol already in the drawing.
  4. Set the symbol height by typing a value in the Height text box.
  5. Set the orientation of the symbol by typing a value in the Angle text box.
  6. Select the Grouping tab at the top of the dialog box.
  7. Click on the plus sign (+) next to each item on the menu tree to expand the tree.
  8. Configure the symbol by selecting the drawing and text parameters you wish to activate. You can see the results in the preview window.
  9. Select the Var Text tab at the top of the dialog box.
  10. Edit text variables selected in step 8 by typing new values into the text boxes.
  11. Select Placement tab.
  12. Click the Place Inst… button.
  13. Select ATTACH TYPE from Menu Manager. Free Point allows you to place the symbol anywhere in the drawing independent of the drawing. All other selections attach the symbol to a drawing entity, allowing the symbol to move with the entity.
  14. Leave Arrow Head selected.
  15. Position the pointer in the drawing and click to place the arrow point of the weld symbol.
  16. Select Done from the Menu Manager.
  17. Position the pointer in the drawing and click to place the body of the symbol. Note that the status indicator in the dialog box indicates the symbol is fully defined.
  18. To edit the symbol select Move, Move Text, Mod Attach… , or Move Origin… from the dialog box.
  19. Click the New Inst button to add another symbol.
  20. Click the OK button to complete the task.

Editing welding symbols in a drawing

You can easily edit any of the symbol parameters after the symbol is placed in a drawing.

  1. Select DETAIL > Modify > Symbol from the Menu Manager.
  2. Select the symbol you wish to change.
  3. The Symbol Instance dialog box will open.
  4. Review and change settings as desired.
  5. Click the OK button to complete the task.